📄 MasterFrame Finite Element (FE) Analysis FAQs: Modelling various Structural Elements

MasterFrame Finite Element (FE) Analysis FAQs: How to Model Various Structural Elements

⚠️

Under Construction

Here is a comprehensive technical breakdown of the most common "How do I model a [X] in MasterFrame Finite Element (FE) Analysis?" support queries.

Each scenario outlines the structural design intent, underlying MasterSeries software behaviour, step-by-step practical workflow, and key engineering limitations.


Concrete Raft Foundation on Soil

  • Design Intent: Modeling ground-bearing foundation mats on elastic soil springs while maintaining horizontal stability.
  • MasterSeries Behaviour: Area (Y)-springs provide vertical subgrade stiffness (k in kN/m^3) but generate zero horizontal frictional resistance. Enabling Compression Only activates a non-linear solver that iteratively deactivates springs in tension zones.
  • Practical Solution:

    1. Create a 2D FE surface using codified concrete (e.g. C28/35).
    2. Under FE Surfaces > Edge/Support Conditions, enter the Y-spring stiffness (k) and tick Compression Only.
    3. Critical Horizontal Stability: Apply minimal corner Nodal Static Supports to prevent matrix singularities without locking the slab in-plane].
  • Limitations & Cautions: Do not fix Dx/Dz continuously around perimeter edges, as this creates artificial membrane stresses that corrupt rebar design. Load cases lacking net stabilizing dead load (e.g., live-load-only or wind uplift) will fail compression-only convergence.


Concrete Core Walls & Shear Walls

  • Design Intent: Modeling vertical stability cores, stairwells, and lift shafts in 3D multi-storey frames.
  • MasterSeries Behaviour: 2D FE shell surfaces represent the wall mid-plane, capturing in-plane membrane actions (\(Fy, τxy) and out-of-plane flexure.
  • Practical Solution:

    1. Create vertical FE surfaces along gridlines using codified concrete.
    2. Apply pinned line support restraints (Quick Set > Pinned) along the bottom edge.
    3. Pass the surfaces to MasterKey Concrete Wall Design to define pier and coupler beam design zones.
  • Limitations & Cautions: Avoid the older "Add Shear Wall" 1D frame method when combining walls with FE floor slabs, as rigid link members can induce artificial stiffness imbalances.


Waffle or Ribbed Concrete Slabs

  • Design Intent: Modeling voided two-way waffle grids or one-way ribbed floor plates.
  • ⚠️ Critical Pitfall: Do NOT select the "Ribbed" FE material setting. "Ribbed" is formulated strictly for one-way composite steel decking profiles and produces incorrect stiffness matrices for concrete slabs.
  • Practical Solution:

    1. Create a 2D FE surface using Isotropic Codified Concrete representing only the thin structural topping slab (e.g., 100-120mm).
    2. Draw 1D line elements along the rib paths and set them as Attached Beams (bottom justified).
    3. Specify only the projecting downstand depth for the beam section. MasterSeries automatically computes the T-beam composite stiffness.
  • Limitations & Cautions: Design downstand ribs in MasterKey Concrete Beam Design using Combined Beam-Plate Results; slab design strips in MasterKey Concrete Slab Design cannot be generated directly over attached T-beam flange widths.


Slabs with Varying Thicknesses, Drop Panels, or Steps

  • Design Intent: Modeling floor slabs with local thickenings, drop panels, or pool pits.
  • MasterSeries Behaviour: FE shell elements lie on their geometric centerline planes. Modeling adjacent 200mm and 400mm slabs on a single flat plane neglects the physical vertical mid-plane offset.
  • Practical Solution:

    • For Drop Panels at Columns: Keep a uniform slab thickness in the FE frame model, and define drop panel geometry (projection and extra depth) inside the Punching Shear Tab of MasterKey Concrete Slab Design.
    • For True Physical Steps: Model separate FE surfaces at their true physical centerline elevations and connect them with vertical "rigid" FE surfaces (density = 0, high E-modulus, same thickness as the thicker slab).
  • Limitations & Cautions: Aligning different slab thicknesses on a single flat plane causes compression force discrepancies across the step.


Filter Stress Singularities at Column / Slab Junctions

  • Design Intent: Eliminating theoretical infinite stress spikes (singularities) where 1D columns intersect 2D FE slab surfaces.
  • MasterSeries Behaviour: Because 1D column nodes have zero physical footprint area, refining the mesh causes calculated stress (Force/Area) to approach infinity at the column node.
  • Practical Solution: Enable "Slab Stiff Column/Wall Mesh Regions" under Analysis > FE Surface Meshing > Global Meshing Options. This alters the FE mesh over member footprints to model physical bearing areas and filter out internal peak stresses.
  • Limitations & Cautions: When designing rebar, use Section Diagrams with Strip Averaging (averaging width le 4 x d) rather than designing to an isolated peak point.


Piled Slabs and Combined Pile Foundations

  • Design Intent: Modeling large foundation mats supported on discrete piles rather than uniform soil.
  • MasterSeries Behaviour: Piles are represented as 1D "stub column" elements or nodal vertical springs beneath the FE slab.
  • Practical Solution: Model the foundation plate as a 2D FE surface using codified concrete. Place short 1D stub columns at pile locations with fixed/pinned base supports or equivalent nodal vertical springs (K in kN/m) derived from allowable pile settlement. Perform punching shear checks around pile heads using the FE Shear Forces Method.
  • Limitations & Cautions: If piles are spaced very closely (<1.5d), punching shear perimeters overlap and strut-and-tie hand checks are required.


Curved Slabs, Curved Shear Walls, or Circular Tanks

  • Design Intent: Modeling circular concrete tanks, curved core walls, or arched slabs.
  • MasterSeries Behaviour: MasterFrame FE shell elements are strictly 8-noded planar (flat) quadrilaterals. A single FE surface cannot be natively curved.
  • Practical Solution: Model the curved wall or slab profile as a series of flat, faceted 2D FE surface segments connected at slight angles (approximating a polygon or cylinder).
  • Limitations & Cautions: Ensure local element coordinate axes are checked for consistent orientation across facet boundaries.


Apply Triangular Earth or Hydrostatic Pressure on FE Walls

  • Design Intent: Applying linearly varying soil pressures or hydrostatic uplift to vertical basement walls or tank base slabs.
  • MasterSeries Behaviour: Area loads can be interpolated linearly across 2D FE surfaces using 3 reference points.
  • Practical Solution: Under FE Surface > Loading, select Area Load, tick Varying Load, enter 3 comma-separated load magnitudes (e.g. 0, 0, 45), and pick 3 corresponding Load Points (LPs) on the mesh surface. For hydrostatic slab uplift, apply positive upward load cases under a dedicated Notional/Variable load set.
  • Limitations & Cautions: Hydrostatic uplift must be grouped separately from standard dead/live loads to ensure correct combination factoring.


Steel Staircase Stringers and Folded Treads

  • Design Intent: Modeling steel stairs for global frame load takedown or dynamic footfall vibration analysis.
  • MasterSeries Behaviour: FE surfaces require 4-sided closed boundary loops to mesh properly.
  • Practical Solution: Model main inclined channel/box stringers as 1D line elements. Frame individual treads and risers using 4-sided boundary lines (or dummy members) and assign thin 2D FE surfaces representing the folded steel plate. Run dynamic analysis across the combined assembly.
  • Limitations & Cautions: Attaching 2D tread surfaces directly to 1D stringer lines at single discrete nodes can create localized numerical stiffness anomalies if the neutral axes do not line up.


Orthotropic Timber Decks or CLT Panels

  • Design Intent: Modeling Cross-Laminated Timber (CLT) floor plates or timber decking with directional stiffness properties.
  • MasterSeries Behaviour: Standard concrete FE surfaces assume isotropic material behavior (Ex = Ey). CLT panels require directional elasticity matrices.
  • Practical Solution: Under FE Surfaces > Material/Thickness, select Orthotropic Material. Manually enter directional Young's moduli (E1, E2) and shear moduli (G12, G13, G23) reflecting the strong and weak grain axes.
  • Limitations & Cautions: The Concrete Slab Design module cannot evaluate rebar or code checks for CLT surfaces -design checks must be performed manually or via Timber Design briefs.


Create Openings in Slabs and Core Walls

  • Design Intent: Modeling stair voids, elevator penetrations, or pipe openings in FE slabs and core walls.
  • MasterSeries Behaviour: Openings are created by defining closed boundary loops inside or along the edge of an FE surface.
  • Practical Solution: Draw the opening perimeter using Dummy Members. Open FE Surfaces > Openings and select the boundary loop to remove the mesh within that zone.
  • Limitations & Cautions: For openings located directly at a slab edge, step the main FE surface boundary inwards rather than using the internal Openings tool to avoid meshing glitches.